Designing for abrasive waterjet fabrication Forethought, flexibility can help cut corners

Forethought, flexibility can help cut corners

By: John H. Olsen, Contributing Writer

April 10, 2007

Thinking ahead during the design stage of a fabrication can save part production time, assembly time, fixturing, and, weld preparation time—and therefore, cost. Designers need to be familiar with abrasive waterjet features to optimize efficiency.

Editor's Note: This article is a modified version of the article that appeared in the May 4, 2004, issue of thefabricator.com.
"Has Taper Sidebar"

Thinking ahead during the design stage of a fabrication always saves manufacturing costs later. This is also true for the parts cut with a precision waterjet—part production time, assembly time, fixturing, and weld preparation time all can be saved. Even design time can be saved by following drafting standards that permit cutting directly from the design's CAD file.

Designers need to be familiar with some abrasive waterjet machining features to minimize overall cost. Some of these concepts also may apply to laser, plasma, and oxyfuel cutting.

Drafting Practices

All projects begin with a design, which usually is prepared with a CAD program. Almost all abrasive waterjet systems accept CAD data (usually a 2-D DXF file) as input for generating the tool path that cuts the part. Carefully preparing an accurate CAD drawing saves time in setting the tool path and helps prevent errors that cause scrap. Specifically, follow these guidelines:

1. Produce accurate drawings. Draw the part exactly to size in the CAD system. If a hole is to be 0.502 inch in diameter, draw it as 0.502 in. and not 0.500 in. with a dimension showing 0.502 in.

2. Close corners. Be certain that corners are closed without gaps or overlapping lines (see Figure 1). Even microscopic errors of this kind can foil automatic tool path generation routines. Most CAD programs provide snaps for joining drawing entities without these defects. Use them.

3. Draw with lines and arcs. Many cutting machines directly accept DXF files containing lines and arcs, but require an intermediate step to convert splines, polylines, blocks, and text to lines and arcs before making the tool path. If you want to draw with these entity types, explode them to lines and arcs before exporting the DXF file.

4. Set tolerances and dimensions carefully and only when necessary. In general, it is not useful to spend time dimensioning and placing tolerances on a part to be made entirely by abrasive waterjet machining. The machine's path is the same no matter what tolerance is specified. An overall tolerance on how close the part must be to the theoretical line is useful for selecting which machine can be used. On the other hand, features that must be controlled tighter than the overall tolerance should be toleranced separately, so that it is evident that a second operation must be performed, such as reaming a hole.

The speed along the path varies according to the surface finish required. For this reason, finish requirements should be indicated. This specification usually is done by using "layers" within the DXF file and is specific for each waterjet machine. Learn how to specify surface quality for the particular machine you will be using.

Avoid manual dimensioning. If dimensions are required for some reason other than the abrasive waterjet machine, use the automatic dimensioning feature of your CAD system. A machine operator's worst nightmare is to make scrap because the DXF file and the dimensioned drawing don't agree.

5. Choose the right file formats. The DXF file is the most popular format for exchanging 2-D CAD data. Unfortunately, there are hundreds of flavors of DXF files, and you may have conversion problems. AutoCAD® release 12 DXF files are the most popular, and almost all programs can import them. Avoid binary DXF files because almost no one supports them.

If you have trouble reading a DXF after it has been sent by e-mail, try using PK-Zip to zip it first. Some e-mail programs recognize a DXF file as a text file and reformat it in a way that makes it useless as a DXF file.

Individual Part Design

The speed at which an abrasive waterjet can cut depends on the shape of the part. Fine, sharp features cut more slowly than large, rounded features. Smooth, striation-free edges take longer to cut than rough severance cuts. Some guidelines follow for designing parts to save time later.

1. Avoid sharp internal corners. An abrasive waterjet must slow down to make precise, sharp internal corners. You can reduce the cutting time by closing a slot with an arc rather than a square end. This is true even when the path length is increased (see Figure 2).

2. Choose the appropriate external corner process. The correct strategy for cutting external corners previously was the same as for internal corners; namely, radius the corners to decrease cutting time. Recently, however, the concept of corner passing has made it possible to make sharp corners by moving past the corner into the scrap at the full cutting speed until the lagging bottom portion of the jet has passed the corner. Then the jet is moved back to the corner quickly and started on its new path. The result is a quickly cut, high-quality corner.

Check whether the machine you use has corner passing. If so, sharp corners are cut the fastest. Otherwise, design the corners with as large a radius as possible to save cutting time.

3. Consider piercing options. With each pierce of the material, you must wait for the jet to turn off from the previous cut, restart for the new cut, and then pierce the material. If there are holes near the periphery of a part, it often is faster simply to connect them to the outside rather than pierce them (see Figure 3).

4. Consider taper. An abrasive waterjet kerf is tapered (see Taking Out Taper Sidebar). When the jet moves slowly, the kerf is widest at the bottom. When it moves fast, the kerf is widest at the top. The jet cuts thin materials at a high speed, so thin materials have greater edge taper than thicker materials. Be sure that your design can tolerate this edge taper. If not, you can move slowly along the portion of the path that must be taper-free, or use a more sophisticated machine that tilts the head to remove taper while cutting at normal speed.

5. Use tabbing to save costs. Tabs on the part edge are used most commonly to hold the part in place while it is being cut. By using tabs, you can cut hundreds of small parts unattended from a single plate without the finished parts snagging the nozzle or falling into the catcher, where they are easily lost.

Tabs also are a useful way to store small parts to minimize handling. Storing in inventory, anodizing, and plating all can be performed on a single sheet of tabbed parts. Then, when the parts are needed, they are broken free like parts in a plastic toy model kit (seeFigure 4).

Assembly and Weldment Design

Forethought about the entire design as an assembly or weldment also can save manufacturing time (see Figure 5). The shape flexibility and the precision possible with abrasive waterjet cutting permit self-jigging assemblies and other useful features for easing assembly.

1. Use tabs and slots to aid assembly. Some of the assembly techniques used in sheet metal work can be used with heavy plates cut with abrasive jets. Slots can be used to precisely receive tabs cut on the mating part. Joining is then achieved by one of three methods:

• The tab extends through the mating plate and is twisted with a wrench to lock the two pieces together.
• The tab is somewhat shorter than the plate thickness and is plug-welded into place.
• The tab is somewhat shorter than the plate thickness and is tapped for bolting into place.

2. Use a constant thickness. If all pieces of a weldment or assembly are the same material and thickness, they all can be cut from the same plate. Small parts can be nested within holes in large parts to save material, and parts for the entire assembly can be made in one setup, saving shop time.

3. Make holes for fasteners and bearings. Abrasive jets make clean, precise holes that either can be tapped or reamed as soon as the part is removed from the machine. Bearings can be pressed directly into reamed holes. Tapped holes provide accurate location and eliminate the need to handle nuts and second wrenches during assembly. Square holes can be used in combination with carriage bolts as another method for eliminating second wrenches at assembly.

Time can be saved in piece-part manufacturing, assembly, and welding by using knowledge of the cutting process to its fullest during the design phase.

Dr. John H. Olsen is co-founder and vice president of operations of OMAX® Corp., 21409 72nd Ave. S., Kent, WA 98032, 253-872-2300, jhoomax@aol.com, www.omax.com.